LAST SEEN ONLINE:
NOV 22, 2026 11:36 UTC
LOCAL_TIME_SYNC:
--:--:-- | -- _
← Digital notebook
CHT and Thermal Simulation 44 min read

Thermal Simulation and Conjugate Heat Transfer — From Fundamentals to Industrial CFD

Learn heat-transfer physics, thermal management, governing equations, material properties, engineering units, boundary conditions, conjugate heat transfer, OpenFOAM workflows, industrial applications, and thermal simulation verification.

1. Introduction: Why Thermal Simulation Matters

Temperature is one of the most important quantities in engineering. It influences material strength, electrical resistance, chemical reaction rates, fluid viscosity, component lifetime, thermal expansion, and system efficiency.

Almost every engineering system must either generate, transport, reject, or control heat.

Consider the following examples:

  • Data centres: Servers generate heat that must be removed without creating local hot spots.
  • Electronics: Processors and power electronics must remain within their allowable junction temperatures.
  • Automotive engineering: Batteries, electric motors, inverters, and power electronics require effective thermal management.
  • Aerospace: Turbine blades, combustion chambers, avionics, and thermal protection systems experience demanding thermal environments.
  • Energy systems: Heat exchangers, boilers, condensers, and thermal storage systems depend on predictable heat-transfer performance.
  • Manufacturing: Welding, casting, additive manufacturing, and heat treatment involve temperature-dependent material behaviour.
  • Buildings and HVAC: Heating, ventilation, air conditioning, and refrigeration depend on controlling energy transport through air, fluids, and solid structures.

Thermal simulation helps engineers understand these processes before committing to expensive prototypes, experiments, or design iterations.

Computational fluid dynamics (CFD) can predict fluid motion and heat transport, while solid heat-transfer models calculate temperature distributions inside components. When these physics interact, conjugate heat transfer (CHT) provides a unified modelling approach.

The purpose of this module is to build an engineering understanding of thermal simulation, beginning with fundamental physics and progressing toward practical CFD workflows.

By the end, you should be able to:

  • Explain conduction, convection, radiation, and thermal energy storage.
  • Identify the governing equations and the assumptions behind them.
  • Understand the physical meaning and units of thermal properties.
  • Define appropriate thermal and flow boundary conditions.
  • Distinguish a simple thermal model from a conjugate heat-transfer simulation.
  • Plan a multi-region thermal CFD case.
  • Interpret temperature, heat flux, pressure drop, and energy balance results.
  • Assess mesh independence, numerical convergence, and physical validity.
  • Understand how thermal CFD supports industrial design decisions.

2. What Is Thermal Simulation?

Thermal simulation is the numerical prediction of temperature, heat transfer, and related thermal quantities in a physical system.

Depending on the problem, the model may calculate:

  • Temperature distribution, T(x,t)T(\mathbf{x},t)
  • Heat flux, q\mathbf{q}
  • Total heat-transfer rate, Q˙\dot Q
  • Fluid velocity and pressure
  • Convective heat-transfer coefficients
  • Thermal energy storage
  • Material-dependent temperature variations
  • Thermal expansion and stress, if coupled to structural mechanics

Here, x\mathbf{x} represents spatial position and tt represents time.

Thermal simulation can be divided into several levels.

2.1 Analytical and lumped thermal models

These use simplified equations, thermal resistances, or average temperatures.

For example, the heat-transfer rate through a thin wall can be approximated by:

Q˙=kAL(T1−T2)\dot Q = \frac{kA}{L}(T_1-T_2)

where kk is thermal conductivity, AA is the transfer area, LL is wall thickness, and T1−T2T_1-T_2 is the temperature difference.

Such models are computationally inexpensive and useful for preliminary design.

However, they cannot fully resolve complex three-dimensional temperature fields or local flow effects.

2.2 Solid thermal simulation

A solid thermal model solves heat conduction inside a component.

Typical examples include:

  • A heated metal plate
  • An electronic circuit board
  • A battery cell
  • A turbine blade
  • An insulated wall

Fluid motion may be excluded, with cooling represented through prescribed temperatures, heat fluxes, or convective boundary conditions.

2.3 Fluid thermal simulation

A fluid thermal simulation solves the flow field together with thermal transport.

It can predict:

  • Fluid temperature changes
  • Thermal boundary layers
  • Natural and forced convection
  • Buoyancy-driven circulation
  • Temperature mixing
  • Heat removal by a cooling stream

2.4 Conjugate heat transfer

A CHT model couples heat conduction in solid regions with heat transport in adjacent fluid regions.

Instead of prescribing the temperature of the solid-fluid interface or assuming a fixed heat-transfer coefficient, the simulation calculates the coupled thermal response from the fluid and solid physics.

For example, in an electronics-cooling problem, the simulation can predict how heat travels from a semiconductor package through a thermal interface material and heat sink before being transferred to cooling air.

This is often essential when the solid’s thermal resistance and the fluid’s convective resistance are both important.


3. The Physics of Heat Transfer

Heat is energy transferred because of a temperature difference.

Three fundamental mechanisms are involved: conduction, convection, and thermal radiation. In some applications, phase change also plays a major role.

3.1 Conduction

Conduction transfers thermal energy through a material due to microscopic energy transport.

It occurs in solids and can also occur in stationary fluids.

Examples include:

  • Heat moving through a metal plate
  • Heat travelling from a processor into a heat sink
  • Heat conduction through an insulation layer
  • Heat spreading through a battery electrode

Fourier’s law describes conductive heat flux:

q=−k∇T\mathbf{q}=-k\nabla T

where:

  • q\mathbf{q}: conductive heat flux, W/m²
  • kk: thermal conductivity, W/(m·K)
  • ∇T\nabla T: temperature gradient, K/m

The negative sign indicates that heat flows in the direction of decreasing temperature.

For one-dimensional conduction through a uniform wall:

Q˙=kAL(T1−T2)\dot Q=\frac{kA}{L}(T_1-T_2)

This expression shows that conductive heat transfer increases with thermal conductivity, area, and temperature difference. It decreases as wall thickness increases.

Engineering interpretation: A highly conductive metal generally spreads heat effectively, whereas a low-conductivity material can act as insulation.

Real materials may have temperature-dependent thermal conductivity. Some composites and crystals also have direction-dependent conductivity, called anisotropic conductivity.

For such materials, conductivity is represented by a tensor rather than a single scalar.

3.2 Convection

Convection involves heat transfer between a surface and a moving fluid. It combines molecular diffusion near the surface with energy transport caused by fluid motion.

Newton’s law of cooling provides a useful engineering representation:

Q˙=hA(Ts−Tf)\dot Q=hA(T_s-T_f)

where:

  • hh: convective heat-transfer coefficient, W/(m²·K)
  • AA: heat-transfer area, m²
  • TsT_s: surface temperature, K
  • TfT_f: representative fluid temperature, K

The coefficient hh depends on the geometry, flow regime, fluid properties, velocity, and thermal boundary-layer behaviour.

Unlike thermal conductivity, hh is generally not a fixed material property.

It is an outcome of the flow and thermal conditions.

For instance, increasing airflow over a heat sink often increases convective heat transfer. However, the resulting pressure drop and fan power may also increase.

This creates an important design trade-off between cooling performance and energy consumption.

Forced convection

Forced convection occurs when a fan, pump, compressor, or other mechanism drives fluid motion.

Examples:

  • Air flowing through a data-centre server
  • Coolant circulating through a battery cold plate
  • Water flowing through a heat exchanger
  • Air passing over an automotive radiator

Natural convection

Natural convection occurs when buoyancy forces drive fluid motion because of density differences caused by temperature variations.

Examples:

  • Warm air rising above a heated electronic component
  • Air circulating around a hot vertical plate
  • Passive cooling of electrical cabinets

Natural convection can be sensitive to gravity direction, enclosure geometry, and the temperature dependence of fluid density.

Mixed convection

Mixed convection occurs when forced flow and buoyancy both influence the thermal field.

This can be important in low-velocity cooling systems and enclosures with substantial temperature differences.

3.3 Thermal radiation

Radiation transfers energy through electromagnetic waves. Unlike conduction and convection, it does not require a material medium.

A simplified expression for the net radiation exchanged between a small surface and a large surrounding enclosure is:

Q˙rad=εσA(Ts4−Tsur4)\dot Q_{\mathrm{rad}} = \varepsilon\sigma A(T_s^4-T_{\mathrm{sur}}^4)

where:

  • ε\varepsilon: surface emissivity, dimensionless
  • σ\sigma: Stefan-Boltzmann constant, approximately 5.670374419×10−85.670374419\times10^{-8} W/(m²·K⁴)
  • TsT_s: absolute surface temperature, K
  • TsurT_{\mathrm{sur}}: effective surrounding temperature, K

This simplified equation assumes a suitable large-surroundings configuration. More complex geometries require view factors or a radiation model.

Important: Temperatures in the fourth-power radiation expression must be absolute temperatures in kelvin, not degrees Celsius.

Radiation can be important in:

  • High-temperature furnaces
  • Combustion systems
  • Turbine environments
  • Thermal protection systems
  • Enclosures containing hot components
  • Low-pressure or vacuum thermal systems

For low-temperature systems, radiation may be less important than convection, but it should not automatically be neglected.

3.4 Phase-change heat transfer

When a material changes phase, energy may be absorbed or released without an equivalent sensible-temperature change.

Examples include:

  • Boiling in a cooling channel
  • Condensation in a heat exchanger
  • Evaporation in refrigeration
  • Melting and solidification in thermal storage

The latent energy associated with a phase change can be expressed as:

Q=mLQ=mL

where mm is mass in kg and LL is the specific latent heat in J/kg.

Phase-change modelling may require additional physics, including interfacial dynamics, phase fractions, nucleation, and boiling or condensation correlations.

A single-phase thermal model is not automatically suitable for these applications.


4. The Governing Equations

Understanding the governing equations is essential for choosing the right solver and interpreting the results.

4.1 Conservation of energy

The first law of thermodynamics states that energy cannot be created or destroyed. It can be transported, converted, or stored.

For a simplified incompressible fluid with constant properties, negligible viscous dissipation, and no additional energy-conversion terms, the temperature equation can be written as:

ρcp(∂T∂t+u⋅∇T)=∇⋅(k∇T)+q˙′′′\rho c_p\left( \frac{\partial T}{\partial t} +\mathbf{u}\cdot\nabla T \right) = \nabla\cdot(k\nabla T)+\dot q'''

where:

  • ρ\rho: density, kg/m³
  • cpc_p: specific heat capacity at constant pressure, J/(kg·K)
  • TT: temperature, K
  • u\mathbf{u}: fluid velocity, m/s
  • kk: thermal conductivity, W/(m·K)
  • q˙′′′\dot q''': volumetric heat generation, W/m³

The equation contains four important contributions.

Transient storage

ρcp∂T∂t\rho c_p\frac{\partial T}{\partial t}

This describes how thermal energy stored locally changes with time.

Advection

ρcpu⋅∇T\rho c_p\mathbf{u}\cdot\nabla T

This represents thermal energy transported by the moving fluid.

Conduction

∇⋅(k∇T)\nabla\cdot(k\nabla T)

This represents thermal energy transported through temperature gradients.

Volumetric heat generation

q˙′′′\dot q'''

This represents internal energy sources such as electrical resistance heating or heat generated by a chemical reaction.

The exact energy equation depends on the physical model. Compressible flows, strongly temperature-dependent properties, reacting flows, and cases with significant viscous dissipation may require a more complete enthalpy or total-energy formulation.

4.2 The solid heat-conduction equation

For a stationary solid with isotropic thermal conductivity:

ρscs∂Ts∂t=∇⋅(ks∇Ts)+q˙s′′′\rho_s c_s\frac{\partial T_s}{\partial t} = \nabla\cdot(k_s\nabla T_s)+\dot q_s'''

The subscript ss denotes solid properties.

If the solid has no internal heat generation and reaches steady state:

∇⋅(ks∇Ts)=0\nabla\cdot(k_s\nabla T_s)=0

If ksk_s is also constant:

∇2Ts=0\nabla^2T_s=0

This is the Laplace equation.

When internal heat generation is present, the temperature field is governed by a Poisson-type equation.

4.3 The fluid-flow equations

Thermal CFD normally solves energy transport together with fluid motion.

For incompressible flow with constant density:

∇⋅u=0\nabla\cdot\mathbf{u}=0

This is the continuity equation.

A simplified momentum equation is:

ρ(∂u∂t+u⋅∇u)=−∇p+∇⋅τ+ρg\rho\left( \frac{\partial\mathbf{u}}{\partial t} +\mathbf{u}\cdot\nabla\mathbf{u} \right) = -\nabla p+\nabla\cdot\boldsymbol{\tau}+\rho\mathbf{g}

where:

  • pp: pressure, Pa
  • τ\boldsymbol{\tau}: viscous stress tensor, Pa
  • g\mathbf{g}: gravitational acceleration, m/s²

For buoyant thermal flows, density variations can drive circulation. Depending on the temperature range and flow regime, these variations may be modelled using the Boussinesq approximation or a more general variable-density formulation.

The energy, momentum, and continuity equations are coupled through velocity, density, temperature, and fluid properties.

4.4 Transient versus steady-state thermal simulation

A steady-state simulation assumes that the calculated fields no longer change with time:

∂T∂t=0\frac{\partial T}{\partial t}=0

This is appropriate when the engineering question concerns a stable operating condition and the steady solution exists.

A transient simulation retains the time-dependent terms and predicts the evolution of temperature.

It is needed for questions such as:

  • How quickly does a battery heat up?
  • How long does an electronic component take to reach its operating temperature?
  • What happens immediately after a cooling fan fails?
  • How does a thermal system respond to a changing heat load?
  • What temperature develops during a startup or shutdown?

A steady-state result cannot tell you how quickly a component reaches that state.


5. Thermal Properties, Engineering Units, and Inputs

Correct material properties are just as important as the geometry and numerical method.

The following table summarizes commonly required quantities.

QuantitySymbolSI unitPhysical meaning
TemperatureTTKThermal state
Densityρ\rhokg/m³Mass per unit volume
Specific heat capacitycpc_pJ/(kg·K)Energy needed per unit mass per kelvin
Thermal conductivitykkW/(m·K)Ability to conduct heat
Dynamic viscosityμ\muPa·sResistance to deformation in a fluid
Kinematic viscosityν\num²/sDynamic viscosity divided by density
Thermal diffusivityα\alpham²/sRate at which temperature disturbances diffuse
Heat fluxq′′q''W/m²Heat-transfer rate per unit area
Volumetric heat generationq˙′′′\dot q'''W/m³Heat generated per unit volume
Total heat-transfer rateQ˙\dot QWEnergy transferred per unit time
Convective coefficienthhW/(m²·K)Convective heat transfer per area and temperature difference
Emissivityε\varepsilonDimensionlessSurface radiation property
Thermal expansion coefficientβ\beta1/KRelative volumetric expansion per kelvin, depending on definition

Thermal diffusivity is defined as:

α=kρcp\alpha=\frac{k}{\rho c_p}

A material with high thermal diffusivity responds rapidly to temperature disturbances, whereas a material with high heat capacity can store substantial energy for a given temperature rise.

5.1 Temperature units

Temperature is commonly specified in kelvin or degrees Celsius.

The conversion is:

T[K]=T[∘C]+273.15T[\mathrm{K}]=T[^\circ\mathrm{C}]+273.15

A temperature difference has the same numerical value in kelvin and degrees Celsius:

ΔT[K]=ΔT[∘C]\Delta T[\mathrm{K}]=\Delta T[^\circ\mathrm{C}]

For example, a temperature rise from 20°C to 60°C corresponds to a 40 K difference.

Always check whether a model input requires absolute temperature or a temperature difference.

5.2 Material properties must match the operating range

Material data may vary significantly with temperature.

Examples include:

  • Air density and viscosity
  • Coolant viscosity and heat capacity
  • Aluminium thermal conductivity
  • Polymer thermal conductivity
  • Battery material properties
  • Thermal interface material conductivity

Using constant properties can be appropriate for a narrow temperature range. For larger temperature changes, temperature-dependent properties may be necessary.

For compressible gas flows, the equation of state and energy formulation must also be consistent with the expected operating conditions.

5.3 Fluid and solid properties are different

A fluid region may require:

  • Density or an equation of state
  • Dynamic viscosity
  • Specific heat capacity
  • Thermal conductivity
  • Turbulence-model inputs
  • Appropriate thermodynamic models

A solid region generally requires:

  • Density
  • Specific heat capacity
  • Thermal conductivity
  • Optional temperature dependence
  • Optional anisotropy

Specific heat capacity is especially important in transient simulations because it determines how much energy is stored for a given temperature change.

For steady conduction with constant properties and no internal sources, multiplying all solid properties by a common time-independent storage factor does not alter the same conduction equation. However, density and heat capacity remain essential for transient behaviour.

5.4 Heat generation inputs

Heat generation can be represented in several ways.

Total power

P=Q˙[W]P=\dot Q \quad [\mathrm{W}]

For a uniformly heated volume VV:

q˙′′′=PV\dot q'''=\frac{P}{V}

For example, a component dissipating 100 W uniformly within a volume of 2×10−42\times10^{-4} m³ has a volumetric heat source of:

q˙′′′=1002×10−4=5×105 W/m3\dot q'''=\frac{100}{2\times10^{-4}} =5\times10^5\ \mathrm{W/m^3}

This conversion is valid only if the heat is actually generated uniformly throughout that volume.

Surface heat flux

If the power is applied over a known area AA:

q′′=PAq''=\frac{P}{A}

Spatially varying heat generation

Some applications require a nonuniform source distribution, such as a processor with multiple active regions or a battery with spatially varying electrical losses.

The source should reflect the actual physics rather than an arbitrary uniform approximation.


6. Dimensionless Numbers in Thermal Engineering

Dimensionless numbers help identify the dominant physics, estimate flow regimes, and compare geometrically different systems.

6.1 Reynolds number

Re=ρULμ=ULνRe=\frac{\rho UL}{\mu}=\frac{UL}{\nu}

The Reynolds number compares inertial and viscous effects.

Here, UU is a characteristic velocity and LL is a characteristic length.

It helps characterize flow behaviour and select suitable turbulence modelling approaches.

6.2 Prandtl number

Pr=να=μcpkPr=\frac{\nu}{\alpha}=\frac{\mu c_p}{k}

The Prandtl number compares momentum diffusivity with thermal diffusivity.

It influences the relative development of velocity and thermal boundary layers.

6.3 Nusselt number

Nu=hLkfNu=\frac{hL}{k_f}

The Nusselt number represents convective heat transfer relative to pure conduction across a characteristic fluid length scale.

Correlations for NuNu are commonly used in preliminary thermal design and heat-exchanger calculations.

6.4 Rayleigh number

For natural convection:

Ra=gβΔTL3ναRa=\frac{g\beta\Delta T L^3}{\nu\alpha}

The Rayleigh number combines buoyancy, viscosity, and thermal diffusion effects.

A high Rayleigh number often indicates stronger buoyancy-driven motion, although the transition and flow structure depend on geometry and boundary conditions.

6.5 Fourier number

Fo=αtL2Fo=\frac{\alpha t}{L^2}

The Fourier number describes transient thermal diffusion relative to the characteristic length scale.

It is useful for understanding heating and cooling times.

6.6 Biot number

Bi=hLcksBi=\frac{hL_c}{k_s}

The Biot number compares internal conductive resistance in a solid with its external convective resistance.

A small Biot number can support a lumped-capacitance approximation, provided the remaining assumptions are appropriate. A large Biot number indicates that significant temperature gradients may develop inside the solid.

These dimensionless groups help determine whether a detailed thermal CFD model is necessary or whether a simpler model may be sufficient.


7. What Is Thermal Management?

Thermal management is the design and operation of a system that controls heat generation, heat transport, and heat rejection to keep temperatures within acceptable limits.

It is broader than thermal simulation.

A thermal management system may contain:

  • Heat sources
  • Heat spreaders
  • Heat sinks
  • Fans and blowers
  • Pumps
  • Coolant channels
  • Radiators
  • Thermal interface materials
  • Insulation
  • Phase-change materials
  • Temperature sensors and control systems

The objective is not always to minimize temperature at any cost. Engineers must balance temperature limits against pressure drop, pumping power, fan power, weight, volume, noise, cost, reliability, and manufacturing constraints.

7.1 Important thermal performance metrics

Depending on the application, useful metrics include:

Maximum component temperature

Tmax⁡=max⁡x∈ΩT(x)T_{\max}=\max_{\mathbf{x}\in\Omega}T(\mathbf{x})

This helps identify thermal-limit violations and hot spots.

Temperature nonuniformity

ΔTcomponent=Tmax⁡−Tmin⁡\Delta T_{\mathrm{component}}=T_{\max}-T_{\min}

This is particularly important for batteries, electronic packages, and components susceptible to thermal gradients.

Thermal resistance

Rth=ΔTQ˙R_{\mathrm{th}}=\frac{\Delta T}{\dot Q}

Its unit is K/W.

Thermal resistance can describe a complete component or a simplified section of the heat-transfer path.

Cooling-fluid temperature rise

ΔTf=Tout−Tin\Delta T_f=T_{\mathrm{out}}-T_{\mathrm{in}}

For a fluid with approximately constant properties and negligible phase change:

Q˙≈m˙cpΔTf\dot Q\approx\dot m c_p\Delta T_f

where m˙\dot m is the mass flow rate in kg/s.

Pressure drop

Δp=pin−pout\Delta p=p_{\mathrm{in}}-p_{\mathrm{out}}

Pressure drop indicates the hydraulic cost of moving coolant through the system.

Cooling-system energy consumption

For a pump, a simplified estimate of fluid power is:

Pfluid=Δp V˙P_{\mathrm{fluid}}=\Delta p\,\dot V

where V˙\dot V is the volumetric flow rate in m³/s.

The required shaft or electrical power is higher when pump efficiency is below 100%.

A good design must remove the required heat while keeping the overall energy cost acceptable.


8. What Is Conjugate Heat Transfer?

Conjugate heat transfer couples the thermal behaviour of solids and fluids.

A typical CHT system contains:

  1. A solid region where heat is conducted.
  2. A fluid region where heat is transported by convection and conduction.
  3. A shared interface where thermal energy passes between the regions.

Consider a metal plate heated by an internal source and cooled by flowing air.

The heat travels through the metal, reaches the surface, and transfers into the air. The resulting air-temperature field influences the surface heat transfer, which in turn influences the temperature inside the plate.

These processes are interdependent.

A CHT simulation solves the relevant fluid and solid equations together and exchanges information across their interfaces.

8.1 Thermal interface conditions

For an ideal interface with perfect thermal contact and no interfacial heat storage:

Ts,interface=Tf,interfaceT_{s,\mathrm{interface}}=T_{f,\mathrm{interface}}

and

qs⋅ns+qf⋅nf=0\mathbf{q}_s\cdot\mathbf{n}_s+ \mathbf{q}_f\cdot\mathbf{n}_f=0

Here, ns\mathbf{n}_s and nf\mathbf{n}_f are outward-facing normals for the solid and fluid regions.

The second equation expresses conservation of heat flux across the interface. The sign convention follows the outward normals.

These conditions ensure that heat leaving one region enters the other when no interface energy storage or additional interface heat source is present.

8.2 Contact resistance

Real interfaces may have imperfect contact because of roughness, gaps, coatings, adhesives, or thermal interface materials.

In such cases, the interface temperature may not be continuous.

A simplified contact-resistance relation is:

Q˙=Ts,1−Ts,2Rcontact\dot Q=\frac{T_{s,1}-T_{s,2}}{R_{\mathrm{contact}}}

where RcontactR_{\mathrm{contact}} is the total thermal contact resistance in K/W.

Alternatively, an area-specific contact resistance may be specified in m²·K/W.

The model must use the correct definition and units. A model with perfect thermal contact may overpredict heat transfer if the real interface has significant resistance.

8.3 Why use CHT instead of a fixed heat-transfer coefficient?

A simpler solid thermal model may use:

q′′=h(Ts−Tf)q''=h(T_s-T_f)

This is useful when the heat-transfer coefficient is known or can be reliably estimated.

However, hh is generally affected by local velocity, turbulence, geometry, and temperature.

In CHT, the fluid-side heat transfer develops from the solved flow and thermal fields rather than being prescribed everywhere as a constant.

CHT is particularly useful when:

  • The flow distribution is complex.
  • Local hot spots are important.
  • The solid thermal conductivity strongly influences surface temperatures.
  • Multiple solid materials are involved.
  • The fluid temperature rises substantially along the cooling path.
  • A fixed heat-transfer coefficient would introduce unacceptable uncertainty.

CHT is not automatically more accurate in every case. It requires more setup, computational resources, and physical input data. A poorly specified CHT model can still produce misleading results.


9. Industrial Applications of Thermal CFD and CHT

9.1 Data-centre cooling

Servers convert electrical power into heat. Airflow distribution determines how effectively that heat is removed.

A data-centre thermal model may include:

  • Server racks
  • Perforated floor tiles
  • Cold and hot aisles
  • Supply-air temperature
  • Fan-driven airflow
  • Equipment heat loads
  • Recirculation zones
  • Containment systems

Important outputs include server inlet temperatures, rack-level airflow, recirculation, pressure distribution, and cooling-system energy requirements.

CHT may be needed when detailed component and enclosure temperatures matter. Larger facility models may use simplified server representations or porous media instead of resolving every electronic component.

9.2 Electronics and semiconductor cooling

Electronic devices have concentrated heat sources and strict temperature limits.

Typical configurations include:

  • Air-cooled heat sinks
  • Liquid-cooled cold plates
  • Vapour chambers
  • Heat pipes
  • Immersion cooling systems
  • Thermal interface materials

A detailed CHT model can predict temperature gradients through the package, substrate, interface material, and cooling structure.

Important considerations include local heat generation, contact resistance, cooling-channel geometry, and the coupling between flow rate and pressure drop.

9.3 Electric-vehicle battery thermal management

Battery systems require temperature control during charging, discharging, and idle periods.

Thermal CFD can evaluate:

  • Cell-to-cell temperature variation
  • Liquid cold-plate design
  • Air cooling
  • Coolant distribution
  • Heat generation during operation
  • Transient heating
  • Cooling-system failure scenarios

A battery model may require electrochemical or experimentally measured heat-generation inputs. Temperature-dependent properties and heat generation may also be needed.

For safety-critical applications, a single-phase thermal model may be insufficient if the objective involves thermal runaway, gas generation, combustion, or propagation between cells.

9.4 Electric motors and power electronics

Electric machines generate losses through electrical resistance, magnetic effects, friction, and other mechanisms.

Thermal models may investigate:

  • Winding temperatures
  • Rotor and stator heat transfer
  • Cooling jackets
  • Oil spray cooling
  • Air-gap heat transfer
  • Inverter cooling

Loss maps from electromagnetic simulation or experiments may provide the heat-source distribution.

A coupled electromagnetic-thermal workflow may be necessary when electrical losses depend strongly on temperature.

9.5 Heat exchangers and process equipment

Heat exchangers rely on heat transfer between fluids separated by a wall.

CHT can be used to investigate wall conduction, local heat flux, temperature distribution, flow maldistribution, and pressure drop.

Depending on the required accuracy, the model may resolve individual passages or use a reduced-order representation.

Boiling, condensation, fouling, and multiphase effects require additional models when they materially affect performance.

9.6 Aerospace and high-temperature systems

Applications include turbine cooling, combustor liners, heat shields, and thermal protection systems.

These problems may require:

  • Temperature-dependent material properties
  • Radiation
  • High-temperature gas properties
  • Conjugate solid-fluid coupling
  • Transient heating
  • Ablation or material degradation models

The appropriate physical models depend on temperature, pressure, chemical composition, and the specific engineering objective.

9.7 HVAC and building thermal management

Thermal CFD can help analyse:

  • Room air circulation
  • Supply and return locations
  • Thermal comfort
  • Radiator performance
  • Ventilation effectiveness
  • Heat transfer through building components

For large buildings, CFD may be combined with building-energy simulation or reduced-order models to account for weather, occupancy, and long-term energy consumption.


10. Choosing the Correct Thermal Modelling Approach

Not every thermal problem requires full CHT.

Engineering questionPossible modelling approach
Temperature through a simple insulated wallAnalytical conduction model
Approximate cooling of a small, nearly uniform solidLumped-capacitance model
Temperature in a component with known surface heat transferSolid thermal simulation
Airflow and temperature around a heated objectFluid thermal CFD
Temperature inside a solid cooled by complex airflowCHT
Heat transfer between several solids and fluid passagesMulti-region CHT
Radiation-dominated high-temperature enclosureThermal model with radiation
Boiling or condensation in a cooling passageMultiphase or phase-change model
Thermal expansion and stressThermal simulation coupled to structural analysis

Start with the simplest model that can answer the engineering question at the required level of confidence.

Increase model complexity when the omitted physics could materially change the design decision.


11. Boundary Conditions: Turning Physics into a Simulation

Boundary conditions define how the computational domain interacts with its surroundings.

A thermal simulation can fail physically even when the solver runs successfully if its boundary conditions do not represent the real system.

11.1 Fixed-temperature boundary

A fixed-temperature condition prescribes the temperature at a boundary:

T=TwT=T_w

This can represent a controlled thermal reservoir or a known surface temperature.

It may be inappropriate when the surface temperature is actually an unknown result of heat transfer.

11.2 Prescribed heat flux

A heat-flux condition prescribes energy transfer per unit area.

For a boundary receiving heat, the sign depends on the solver’s normal and flux conventions. Always check how the software defines positive heat flux.

A uniform prescribed flux is appropriate only when the applied heat load is reasonably uniform over the selected surface.

11.3 Volumetric heat source

An internal source is used when heat is generated throughout a material volume.

Examples include:

  • Joule heating
  • Distributed component losses
  • Chemical heat release
  • Simplified battery heat generation

The input must have the correct dimensions, usually W/m³ for volumetric power density.

11.4 Convective boundary condition

A convective boundary condition is often written as:

q′′=h(Ts−T∞)q''=h(T_s-T_\infty)

where T∞T_\infty is the ambient or bulk-fluid temperature used by the model.

This condition approximates heat transfer to a fluid without explicitly solving its flow field.

The coefficient hh must be justified by experimental data, correlations, or another suitable analysis.

11.5 Inlet boundary conditions

A fluid inlet may require:

  • Velocity or mass flow rate
  • Temperature
  • Turbulence quantities
  • Pressure or thermodynamic state, depending on the formulation
  • Species or phase information, if relevant

A thermal simulation with a prescribed inlet temperature but no physically meaningful flow rate may not represent the actual cooling performance.

For a cooling stream, the mass flow rate is often one of the dominant inputs.

11.6 Outlet boundary conditions

Outlet conditions must allow the intended flow and thermal field to leave the domain without introducing artificial constraints.

Pressure-based outlet conditions are common, but the exact combination depends on the solver and flow regime.

Temperature conditions at outlets must also be selected consistently with the software formulation.

A zero temperature gradient can be suitable for certain outflow boundaries. It should not be applied blindly where there is substantial reverse flow or where the boundary is too close to the region of interest.

11.7 Natural-convection boundaries

Natural convection requires the correct buoyancy treatment.

Relevant inputs can include:

  • Gravity magnitude and direction
  • Reference density or an equation of state
  • Thermal expansion coefficient, where applicable
  • Temperature-dependent fluid properties
  • Appropriate thermal boundary conditions

The Boussinesq approximation assumes that density variations are small enough to be neglected in most equations but retained in the buoyancy term. It is not suitable for every temperature range or flow.

11.8 Radiation boundaries

Radiation modelling may require:

  • Surface emissivity
  • Surrounding temperature
  • Radiation properties
  • View factors or a radiation transport model
  • Appropriate treatment of participating media, where relevant

The simplest radiation boundary condition may be adequate for an isolated surface exchanging radiation with large surroundings. Complex enclosures may require a more detailed treatment.

11.9 Coupled solid-fluid interface

In CHT, the shared interface must exchange heat consistently between the fluid and solid regions.

The interface conditions must match the solver’s multi-region framework.

Do not independently prescribe unrelated fixed temperatures on both sides of an interface unless that is the intended physical model.

For a standard perfect-contact interface, heat leaving one region must enter the other, with compatible temperature and flux coupling.

11.10 Initial conditions

Transient thermal models require an initial temperature field.

Depending on the problem, the initial state may be:

  • Uniform ambient temperature
  • A measured temperature distribution
  • A previously converged steady-state solution
  • A spatially varying temperature from another simulation

The initial conditions can strongly affect transient results, especially when thermal storage is important.


12. A Practical Thermal CFD Workflow

A reliable workflow begins with the engineering question, not the solver.

Step 1: Define the objective

Write down the question the simulation must answer.

Examples:

  • Is the maximum processor temperature below its limit?
  • Can a cold plate remove 500 W of heat?
  • What coolant flow rate is required?
  • Does a design reduce hot spots?
  • What is the pressure-drop penalty of additional cooling channels?
  • How long does a component take to reach its operating temperature?

Define measurable acceptance criteria before generating the mesh.

Step 2: Gather the engineering inputs

Collect:

  • Geometry and dimensions
  • Materials and thermal properties
  • Heat loads and their spatial distribution
  • Inlet temperature and flow rate
  • Ambient conditions
  • Operating pressure
  • Cooling-system constraints
  • Radiation or contact-resistance data
  • Experimental measurements for validation

Document uncertain inputs and their sources.

A high-resolution mesh cannot compensate for an unrealistic heat load or incorrect material properties.

Step 3: Estimate the thermal behaviour

Perform simple calculations before CFD.

Estimate total heat load, cooling-fluid temperature rise, conductive resistance, and required flow rate.

For a single-phase coolant with approximately constant specific heat:

m˙=Q˙cpΔTf\dot m=\frac{\dot Q}{c_p\Delta T_f}

Suppose a system must remove 500 W, and the cooling fluid is allowed to warm by 5 K. If the coolant has cp=4180c_p=4180 J/(kg·K), the required mass flow rate is approximately:

m˙=5004180×5≈0.0239 kg/s\dot m=\frac{500}{4180\times5} \approx0.0239\ \mathrm{kg/s}

This is a first-order energy-balance estimate, not a final design result.

The actual system must also satisfy pressure-drop, flow-distribution, local-temperature, and operational constraints.

Step 4: Simplify the geometry carefully

Remove geometric details that do not influence the engineering question.

Retain features that control:

  • Flow separation
  • Pressure drop
  • Thermal resistance
  • Contact areas
  • Thin conduction paths
  • Narrow cooling passages
  • Important hot spots

Do not remove a thin thermal interface layer if its resistance is a central part of the problem.

Step 5: Create the computational regions

For a solid-only thermal problem, create the solid computational domain.

For CHT, identify and separate:

  • Fluid regions
  • Solid regions
  • Internal interfaces
  • External walls
  • Inlets and outlets
  • Heat-source regions

Each region must be assigned the correct physical model.

The region topology should reflect the actual heat-transfer paths.

Step 6: Generate the mesh

Mesh resolution should be concentrated where temperature and velocity gradients are expected.

Important locations include:

  • Fluid-solid interfaces
  • Thermal boundary layers
  • Narrow passages
  • Leading edges and flow separation zones
  • Heat-source regions
  • Thin solid layers
  • Sharp geometric changes

For solid conduction, resolve thicknesses and gradients that determine thermal resistance.

For fluid flow, resolve the near-wall flow and thermal fields to a level appropriate for the selected turbulence treatment.

Check mesh quality, cell volumes, non-orthogonality, skewness, and interface connectivity.

Step 7: Select the physical models

Decide whether the problem needs:

  • Steady or transient simulation
  • Incompressible or compressible flow
  • Laminar or turbulent flow
  • Natural or forced convection
  • Temperature-dependent properties
  • Radiation
  • Volumetric heat sources
  • Contact resistance
  • Phase change
  • Thermal-fluid coupling

Use physical estimates and relevant correlations to support these choices.

Step 8: Specify material properties

Assign the correct properties to every region.

For each solid, define density, heat capacity, and thermal conductivity as required by the chosen formulation.

For each fluid, define the appropriate thermophysical and transport properties.

Confirm that the properties are valid over the expected temperature range.

Step 9: Define boundary and interface conditions

Specify inlet flow and temperature, outlet conditions, wall conditions, heat generation, and external thermal interactions.

For CHT, configure the coupled interfaces according to the chosen solver and software version.

Verify units, signs, and reference values.

Step 10: Configure the numerical solution

Choose suitable:

  • Discretization schemes
  • Pressure-velocity coupling
  • Linear solvers
  • Relaxation factors, where applicable
  • Time step for transient calculations
  • Convergence criteria
  • Output and monitoring settings

For transient problems, select the time step based on the relevant flow and thermal time scales, temporal accuracy, and numerical stability requirements.

Step 11: Run and monitor the simulation

Monitor more than residuals.

Useful quantities include:

  • Maximum and minimum temperatures
  • Heat removed through each outlet or boundary
  • Total heat input
  • Pressure drop
  • Mass-flow balance
  • Energy balance
  • Temperature at critical points
  • Changes in key quantities between iterations or time steps

A small residual alone does not guarantee an accurate or physically correct thermal solution.

Step 12: Post-process the results

Inspect:

  • Temperature contours in solids and fluids
  • Heat-flux distributions
  • Velocity and pressure fields
  • Local hot spots
  • Thermal gradients
  • Cooling-flow distribution
  • Heat-source regions
  • Interface heat transfer
  • Pressure drop and pumping requirements

Calculate integrated quantities in addition to viewing contours.

Step 13: Verify, validate, and refine

Perform mesh refinement, appropriate time-step refinement, conservation checks, and comparison against analytical, benchmark, or experimental data.

Only after the model demonstrates suitable credibility should its results be used to support a design decision.


13. A Practical OpenFOAM Workflow

OpenFOAM provides multiple approaches to thermal simulation. The correct choice depends on the installed distribution and version, the physical model, and whether solid and fluid regions must be coupled.

13.1 Start by identifying the solver

Examples include:

  • laplacianFoam: a basic scalar diffusion equation, useful for simple diffusion demonstrations.
  • buoyantSimpleFoam: steady buoyant flow with heat-transfer physics in supported configurations.
  • buoyantPimpleFoam: transient buoyant flow with thermal physics in supported configurations.
  • chtMultiRegionFoam: multi-region conjugate heat transfer, including fluid and solid regions.
  • chtMultiRegionSimpleFoam: available in some OpenFOAM distributions for steady multi-region CHT.

Solver names and capabilities differ across OpenFOAM distributions and versions. Check the documentation and tutorials installed with your own version before selecting a solver.

A simple Laplacian case is useful for learning conduction, but it is not a substitute for a coupled CHT simulation.

13.2 Understand the case structure

A conventional OpenFOAM case contains:

  • 0/: initial and boundary fields
  • constant/: geometry, mesh, physical properties, and model configuration
  • system/: numerical schemes, solver controls, and run settings

A multi-region CHT case has additional region-specific configuration. The exact directory structure depends on the OpenFOAM distribution and case-generation approach.

Typical multi-region inputs may include:

  • Region definitions
  • Separate fluid and solid meshes
  • Region-specific initial fields
  • Fluid thermophysical properties
  • Solid thermophysical properties
  • Turbulence configuration for fluid regions
  • Coupled interface conditions
  • Numerical schemes and solver settings

13.3 Create and check the mesh

For a simple geometry, blockMesh may be sufficient.

For complex geometry, snappyHexMesh can be used to generate a body-fitted mesh around triangulated surfaces.

A typical mesh-quality check is:

checkMesh

For multi-region cases, verify that all regions and interfaces have been generated correctly using the tools supported by your installed version.

13.4 Configure the thermal model

For a single fluid region, confirm that the energy equation, fluid properties, turbulence model, and thermal boundary conditions are consistent with the solver.

For CHT, confirm that:

  • Each region is correctly identified as fluid or solid.
  • Every region has the required thermophysical data.
  • Solid regions have suitable conductivity and thermal storage properties.
  • Fluid regions have appropriate flow and thermal properties.
  • Interface patches are coupled correctly.
  • Heat sources are applied to the intended regions.
  • Radiation and contact resistance are included if required by the physics.

13.5 Run the case

The actual commands depend on the case setup and OpenFOAM distribution.

A typical serial workflow might look like:

checkMesh
foamRun

However, foamRun is not a universal replacement for every solver executable. Some distributions use specific solver applications or different run scripts.

Use the run command specified by the selected tutorial and solver.

For multi-region simulations, follow the region-specific mesh preparation and execution sequence for your version.

13.6 Post-process the results

ParaView is commonly used to inspect temperature, velocity, pressure, and heat-transfer fields.

Useful checks include:

  • Does temperature vary in the expected direction?
  • Is the heat source represented correctly?
  • Is the fluid warming or cooling consistently with the energy balance?
  • Are hot spots located in physically plausible regions?
  • Is heat transferred consistently across interfaces?
  • Are the predicted pressure drop and flow distribution reasonable?

A successful run only demonstrates that the numerical process completed. It does not establish that the physics or results are correct.


14. Steady-State and Transient CHT: Practical Differences

A steady-state CHT simulation seeks a time-independent solution.

It is appropriate when the design objective concerns stable operation and thermal storage does not need to be resolved.

A transient CHT simulation accounts for the thermal energy stored in both fluid and solid regions.

It is necessary when the question involves:

  • Startup and shutdown
  • Changing heat loads
  • Thermal cycling
  • Intermittent operation
  • Cooling failure
  • Temperature response over time

A metal heat sink may have a substantial thermal mass. Even if the cooling air responds quickly, the solid can take much longer to reach a new operating temperature.

The time step should therefore be selected with attention to both fluid and solid time scales.

For transient simulations, check temporal refinement as well as mesh refinement. A fine mesh with an excessively large time step can still produce inaccurate results.


15. Turbulence and Thermal Boundary Layers

In many industrial cooling applications, the flow is turbulent or transitions between laminar and turbulent regimes.

Turbulence affects heat transfer because it changes the transport of momentum and thermal energy.

The choice of turbulence model influences:

  • Velocity profiles
  • Separation and recirculation
  • Wall shear stress
  • Turbulent heat flux
  • Local heat-transfer coefficients
  • Pressure drop

Common RANS models include the kk-ε\varepsilon and kk-ω\omega families, including SST variants.

No turbulence model is universally best. Model selection depends on geometry, flow regime, near-wall treatment, available validation data, and required accuracy.

15.1 Near-wall resolution and y+y^+

The dimensionless wall distance is:

y+=uτyνy^+=\frac{u_\tau y}{\nu}

where:

  • uτu_\tau: friction velocity, m/s
  • yy: wall-normal distance from the wall to the first cell-centre location, m
  • ν\nu: kinematic viscosity, m²/s

The first-cell height and prism-layer distribution should be consistent with the selected wall treatment.

For a wall-resolved SST approach, a common target is y+y^+ near 1. Wall-function approaches typically require a different range determined by the specific model and software implementation.

These are not universal rules for every turbulence model.

Thermal boundary-layer resolution must also be considered. The mesh needed to capture a strong temperature gradient may not be identical to the mesh needed to resolve the velocity field.

Check the documentation for the chosen turbulence and thermal-wall treatment before finalizing the mesh.


16. Mesh Independence and Numerical Verification

Thermal predictions can be sensitive to mesh resolution, especially near heat sources, thin layers, and fluid-solid interfaces.

A mesh-independence study compares a quantity of interest across systematically refined meshes.

Possible quantities include:

  • Maximum solid temperature
  • Average heat-transfer rate
  • Pressure drop
  • Outlet temperature
  • Heat flux through a critical interface

For example:

MeshCell countMaximum temperaturePressure drop
Coarse100,00082.5°C1,150 Pa
Medium250,00080.9°C1,190 Pa
Fine600,00080.4°C1,202 Pa

These values are illustrative only.

The temperature and pressure drop approach limiting values as the mesh is refined, but the required accuracy must be judged against the engineering purpose.

Do not conclude that a simulation is mesh-independent solely because the contours look similar.

Where appropriate, use systematic refinement, observed convergence order, Richardson extrapolation, or a Grid Convergence Index (GCI) procedure.

Verification should also include:

  • Residual and monitor convergence
  • Mass conservation
  • Energy conservation
  • Time-step sensitivity for transient calculations
  • Sensitivity to important modelling assumptions

17. Energy Balance: One of the Most Important Checks

An energy balance is one of the strongest practical checks for a thermal simulation.

For a steady system with no significant energy storage, the net heat input should balance the net heat output and any other relevant energy transfers.

A simplified balance is:

Q˙in−Q˙out≈0\dot Q_{\mathrm{in}} - \dot Q_{\mathrm{out}} \approx 0

The full balance may need to include:

  • Volumetric heat generation
  • Heat entering through boundaries
  • Heat leaving through fluid outlets
  • Radiation
  • Work or energy conversion terms
  • Any other energy sources and sinks included in the model

For a transient system:

dEstoreddt=Q˙in−Q˙out+Q˙generated\frac{dE_{\mathrm{stored}}}{dt} = \dot Q_{\mathrm{in}} - \dot Q_{\mathrm{out}} + \dot Q_{\mathrm{generated}}

This simplified expression assumes that the other relevant energy-transfer terms are either negligible or included in the definitions.

A large energy imbalance can indicate:

  • Incorrect boundary conditions
  • Missing or duplicated heat sources
  • Incorrect interface coupling
  • Insufficient convergence
  • Inappropriate numerical settings
  • Post-processing that omits important boundaries

A credible thermal result should be supported by an energy balance consistent with the solver’s formulation and the desired accuracy.


18. Verification Versus Validation

These terms are related but not interchangeable.

Verification asks: Are we solving the selected mathematical model correctly?

It includes checks of numerical implementation, convergence, conservation, mesh resolution, and time-step sensitivity.

Validation asks: Does the mathematical model adequately represent the real physical system for the intended use?

Validation may compare simulation results against:

  • Experimental temperature measurements
  • Heat-transfer correlations
  • Published benchmark cases
  • Manufacturer performance data
  • Instrumented prototype tests

For thermal CFD, compare the quantities that matter to the design: surface temperatures, outlet temperatures, heat-transfer rates, pressure drops, and temperature distributions.

Agreement at one measurement point does not necessarily validate the entire field.

Experimental uncertainty, sensor placement, contact resistance, and uncertainty in the actual heat load should be considered when interpreting discrepancies.


19. Common Thermal Simulation Mistakes

Mistake 1: Applying an arbitrary heat-transfer coefficient

A guessed value of hh can dominate the predicted temperature.

Better practice: Use experimental data, suitable correlations, or solve the fluid field when the local heat transfer is central to the problem.

Mistake 2: Confusing total power with heat flux

Watts and watts per square metre are different quantities.

Better practice: Check whether the model requires total power, surface heat flux, or volumetric heat generation.

Mistake 3: Using the wrong material properties

Incorrect conductivity or heat capacity can lead to misleading results.

Better practice: Use documented properties at the relevant operating conditions.

Mistake 4: Ignoring thermal contact resistance

Perfect contact may overpredict heat transfer through interfaces.

Better practice: Assess whether an interface resistance or explicit interface material is necessary.

Mistake 5: Using an unsuitable turbulence or wall treatment

An inconsistent near-wall mesh can undermine heat-transfer predictions.

Better practice: Select the mesh and wall treatment together.

Mistake 6: Ignoring radiation

Radiation can be important in high-temperature environments or enclosures.

Better practice: Estimate its possible contribution before neglecting it.

Mistake 7: Assuming that solver convergence means physical accuracy

A converged solution can still use incorrect assumptions or inputs.

Better practice: Perform conservation checks, sensitivity studies, and validation.

Mistake 8: Optimizing temperature alone

A design may reduce peak temperature while increasing pumping power or pressure drop.

Better practice: Evaluate thermal performance alongside hydraulic and energy costs.

Mistake 9: Using a steady-state model for a transient question

A steady-state solution cannot predict warm-up time or thermal response after a failure.

Better practice: Match the model to the time-dependent engineering question.

Mistake 10: Ignoring uncertainty

Material properties, heat loads, contact resistance, and operating conditions are rarely known perfectly.

Better practice: Identify influential uncertain parameters and assess how they affect the design decision.


20. Thermal Design Optimization

Once a model has been verified and validated to an appropriate level, it can support design optimization.

Possible design variables include:

  • Cooling-channel diameter
  • Channel spacing
  • Fin height and thickness
  • Heat-sink geometry
  • Coolant flow rate
  • Inlet temperature
  • Material selection
  • Contact resistance
  • Fan speed
  • Pump operating point

A thermal objective may be:

min⁡Tmax⁡\min T_{\max}

But practical engineering optimization is often multi-objective:

min⁡(Tmax⁡,Δp,Pcooling)\min\left(T_{\max},\Delta p,P_{\mathrm{cooling}}\right)

subject to constraints such as:

Tmax⁡≤TlimitT_{\max}\leq T_{\mathrm{limit}} Δp≤Δpallowable\Delta p\leq \Delta p_{\mathrm{allowable}}

The design may also be constrained by mass, volume, manufacturing limits, noise, reliability, and cost.

An efficient workflow is:

  1. Establish a verified baseline.
  2. Identify the dominant thermal resistances.
  3. Determine which parameters most strongly affect the performance metrics.
  4. Run controlled parameter studies.
  5. Compare designs using consistent criteria.
  6. Check whether improvements persist under realistic operating variation.
  7. Re-verify the final design.

Automated parameter sweeps and scripted post-processing can make this process reproducible and reduce manual errors.


21. A Complete Pre-Run Checklist

Before launching a thermal CFD or CHT simulation, confirm the following.

Physics and engineering inputs

  • The engineering objective and acceptance criteria are defined.
  • The operating conditions and heat loads are documented.
  • Material properties are appropriate for the temperature range.
  • Steady-state or transient behaviour is selected correctly.
  • Radiation, buoyancy, contact resistance, and phase change have been assessed.

Geometry and mesh

  • Relevant heat-transfer paths are retained.
  • Fluid and solid regions are correctly defined.
  • Important thermal gradients are adequately resolved.
  • Mesh quality has been checked.
  • Fluid-solid interfaces are connected and correctly identified.

Boundary conditions

  • Inlet velocity or mass flow rate is physically justified.
  • Inlet temperature is correct.
  • Outlet conditions are suitable for the flow.
  • Heat-source magnitudes and units are correct.
  • External thermal conditions represent the real environment.
  • Coupled interfaces use compatible conditions.

Numerical setup

  • The selected solver supports the required physics.
  • Thermophysical and turbulence models are consistent.
  • Discretization and solver settings are suitable.
  • Transient time steps are sufficiently small for the required accuracy.
  • Critical quantities and conservation metrics are monitored.

Verification and validation

  • Residuals and engineering monitors converge appropriately.
  • Mass and energy balances are checked.
  • Mesh sensitivity is assessed.
  • Time-step sensitivity is assessed for transient cases.
  • Results are compared with relevant analytical, benchmark, or experimental data.

22. A Suggested Learning Path

If you are beginning thermal CFD, avoid starting with a complicated battery pack or data-centre model.

Build understanding progressively.

Stage 1: Pure conduction

Model a one-dimensional wall or heated plate.

Learn Fourier’s law, thermal conductivity, heat flux, temperature gradients, and energy conservation.

Compare the numerical solution against the analytical result.

Stage 2: Convection in a fluid

Model a heated plate in a flowing fluid.

Study the velocity field, thermal boundary layer, Reynolds number, Nusselt number, and sensitivity to inlet conditions.

Stage 3: Natural convection

Study a differentially heated cavity.

Investigate buoyancy, the Rayleigh number, thermal circulation, and mesh sensitivity.

Stage 4: Solid-fluid conjugate heat transfer

Introduce a solid plate or heat sink coupled to a cooling stream.

Investigate interface coupling, solid conduction, fluid convection, and overall energy balance.

Stage 5: Realistic thermal management

Build a heat-sink, cold-plate, or simplified electronics-cooling model.

Add realistic heat sources, material properties, pressure-drop evaluation, and design constraints.

Stage 6: Verification and optimization

Perform mesh and time-step studies, compare against reference data, and automate parameter sweeps.

Document every assumption and make the workflow reproducible.

This progression develops physical intuition before introducing the complexity of industrial geometries.


23. Final Takeaways

Thermal simulation connects thermodynamics, heat transfer, fluid mechanics, numerical methods, and engineering design.

The most important lessons are:

  1. Understand the physics first. Know whether conduction, convection, radiation, storage, or phase change dominates the problem.
  2. Use physically meaningful inputs. Heat loads, material properties, operating conditions, and boundary conditions determine what problem is actually being solved.
  3. Choose the simplest suitable model. A lumped thermal model, solid conduction model, fluid CFD model, and CHT model answer different questions.
  4. Treat fluid and solid regions consistently. In CHT, interface heat transfer must conserve energy.
  5. Resolve the important gradients. Mesh quality and resolution influence both fluid and solid temperature predictions.
  6. Evaluate more than temperature. Pressure drop, cooling-system power, temperature uniformity, and energy balance can be equally important.
  7. Verify and validate the result. Convergence is necessary, but not sufficient, for engineering confidence.
  8. Use simulation to support decisions. A model is most valuable when it helps engineers compare designs, understand trade-offs, and reduce uncertainty.

A successful thermal simulation is not defined by a colourful temperature contour. It is defined by a physically defensible model, consistent numerical results, and evidence that the predictions are reliable enough for the engineering decision.


24. References and Further Reading

The following references provide useful starting points for heat-transfer fundamentals, industrial thermal modelling, OpenFOAM, and numerical verification.

  1. NASA Glenn Research Center — Heat Transfer
    An accessible introduction to heat-transfer mechanisms and thermodynamic fundamentals.
    https://www1.grc.nasa.gov/beginners-guide-to-aeronautics/heat-transfer-3/

  2. NASA — Introduction to Numerical Methods in Heat Transfer
    A technical resource for numerical heat-transfer modelling and governing equations.
    https://ntrs.nasa.gov/api/citations/20200006182/downloads/Introduction%20to%20Numerical%20Methods%20in%20Heat%20Transfer.pdf

  3. ASHRAE Handbook — Heat Transfer
    A reference for heat-transfer principles and applications relevant to HVAC and thermal engineering.
    https://handbook.ashrae.org/Handbooks/F25/SI/f25_ch04/f25_ch04_si.aspx

  4. OpenFOAM User Guide
    Official documentation covering case setup, mesh generation, physical models, boundary conditions, numerical schemes, and post-processing.
    https://www.openfoam.com/documentation/user-guide

  5. OpenFOAM — chtMultiRegionFoam
    Solver documentation for multi-region fluid-solid heat transfer. Check your installed version for the applicable solver options and tutorial cases.
    https://doc.openfoam.com/2212/tools/processing/solvers/rtm/heat-transfer/chtMultiRegionFoam/

  6. OpenFOAM — Heat-Transfer Solvers
    Overview of supported heat-transfer solver families.
    https://doc.openfoam.com/2312/tools/processing/solvers/rtm/heat-transfer/

  7. CFD Direct — Thermal Boundary Conditions
    Explanation of thermal boundary conditions, including external-temperature and coupled-temperature approaches. Check compatibility with your OpenFOAM distribution and version.
    https://doc.cfd.direct/openfoam/user-guide-v14/thermal-boundary-conditions

  8. NASA — Overview of CFD Verification and Validation
    Explains why numerical verification and physical validation are both necessary for credible CFD predictions.
    https://www.grc.nasa.gov/www/wind/valid/tutorial/overview.html

  • Begin with NASA’s heat-transfer fundamentals.
  • Review the governing equations and numerical heat-transfer material.
  • Study the OpenFOAM User Guide before building your first thermal case.
  • Follow the multi-region CHT documentation when introducing solid-fluid coupling.
  • Use NASA’s verification and validation guidance when assessing the reliability of your results.